How to Implement XEBEC Deburring Tool Path (XZY Turn-Mill Machines)

This section offers an example of implementing XEBEC Deburring Tool Path into the machining program.
G-codes and all other details are based on MELDAS controls. Make sure to use appropriate codes for your machine tool.

Machining Operations
  • Workpiece Shape
    Outer Diameter Φ30mm x Inner Diameter Φ20mm
  • Previous Operation
    Drilled a Φ10mm hole that crosses orthogonally and on-center with the centerline of the workpiece
  • Target Edge to be Deburred
    Upper and Lower edges of the inner diameter at the intersection of the Φ10 hole and the Φ20 hole


      [Workpiece]

               

OP 1: Drilling
               

OP 2: Deburring Upper Edge
   

OP 3: Deburring Lower Edge

 



Program Overview
Main Program
O0001 (MAIN PROG);
G0G18; Select XY plane
N1(10DRILL/T1H1); Drilling the Φ10 hole
M05;
M69; Main spindle unclamp
G98M45; Feed per minute and C-axis engage
G00G28H0.0; Return C-axis to machine zero
G28V0.0; Return Y-axis to machine zero
G00T0101; Call T01 drill and tool length offset
G54X40.0Z50.0C0.0; Set the work offset zero position
G97S5000M13; Milling rotation in CW direction
Z-15.0Y0.0M08; Position ZY axes at the hole center
M68; Main spindle clamp
G83X-40.0R-2.0F500; Spot drilling cycle G83
G80; Cancel drilling cycle
G00X40.0Z50.0M69; Main spindle unclamp
G28U0.0W0.0M05; Return XZ axes to machine zero
M09;
M01;

N2(5.8BURRS CUTTER/T0202); Deburring operation
M05;
M69; Main spindle unclamp
G98M45; Feed per minute and C-axis engage
G00G28H0.0; Return C-axis to machine zero
G28V0.0; Return Y-axis to machine zero
G00T0202; Call T02 Back Burr Cutter and tool length offset
G54X40.0Z50.0C0.0; Set the work offset zero position
G97S6000M13; Milling rotation in CW direction
Z-15.0Y0.0M08; Position ZY-axis at the Start Point for Upper Edge
M68; Main spindle clamp
G01X20.0F3000; Position X-axis at the Start Point for Upper Edge
F1000; Set feed rate for the deburring operation
M98P0002; Call subprogram O0002 (XEBEC Deburring Tool Path for Upper Edge)
G01Z-15.0Y0.0F3000; Position ZY-axis at the Start Point for Lower Edge
X-20.0; Position X-axis at the Start Point for Lower Edge
F1000; Set feed rate for the deburring operation
M98P0003; Call subprogram O0003 (XEBEC Deburring Tool Path for Lower Edge)
G00X40.0;
Z50.0M69; Main spindle unclamp
G28U0.0W0.0M05; Return XZ axes to machine zero
M09;
M01;
M30; Program end
Upper Edge Deburring Subprogram
O0002(UPPER EDGE SUB PROG);
U0.000V0.000W0.000;

XEBEC Deburring Tool Path
U-11.293V0.000W0.000;
U0.000V2.564W0.000;
U0.017V-0.027W0.434;
U0.046V-0.077W0.409;

U-0.072V0.126W0.390;
U-0.048V0.080W0.419;
U-0.017V0.028W0.442;
U0.000V-2.564W0.000;
U11.293V0.000W0.000;
M99; Return to main program
Lower Edge Deburring Subprogram
O0003(LOWER EDGE SUB PROG);
U0.000V0.000W0.000;

XEBEC Deburring Tool Path
U-0.307V0.000W0.000;
U0.000V2.564W0.000;
U-0.017V-0.027W0.434;
U-0.046V-0.077W0.409;

U0.072V0.126W0.390;
U0.048V0.080W0.419;
U0.017V0.028W0.442;
U0.000V-2.564W0.000;
U0.307V0.000W0.000;
M99; Return to main program
  • Make sure to use appropriate codes for the X-axis and Y-axis controller modes (diameter or radius).
  • Implementation is similar for XZC turn-mill machines, but in case of XZC turn-mill machine, make sure to turn on polar interpolation prior to Deburring Tool Path codes.
XEBEC